Defining Ansys Superelement SUB File Manually

Photo by James Owen on Unsplash

A surprisingly popular blog-post written here is Exporting Stiffness Matrix from Ansys. A sensible follow up question is what can one do with the exported stiffness matrix? In a recent Xansys Forum post, a question was raised on how we can edit the stiffness matrix of a superelement and use it for our model. 

An approach presented below is to first create a superelement that has the same number of DOF and nodal location that will serve as a template. An APDL script can then be written to edit the stiffness matrix entries as desired before exporting to a new superelement *.SUB file for use in future models. The self-contained script below demonstrates this. 

et,1, 185
mp, ex, 1, 200e3
mp, prxy, 1, 0.33

w = 0.1 ! single element (note nodal locations)
n, 1, w, -w, -w
n, 2, w, w, -w
n, 3, -w, w, -w
n, 4, -w, -w, -w
n, 5, w, -w, w
n, 6, w, w, w
n, 7, -w, w, w
n, 8, -w, -w, w
e, 1, 2, 3, 4, 5, 6, 7, 8

antype, substr     ! analysis type: substructure
seopt, myse,1   ! saves stiffness matrix
m, all, all

! Imports sub info into APDL-math form
*DMAT, myse, d, import, sub, myse.sub, stiff

! Export to apdl array for editing
*EXPORT, myse, apdl, apdlmat

! Make edits as desired
apdlmat(2,2) = 28 ! example edit to be checked later

! Put back to APDL-math form
*DMAT, myse, ,import, apdl, apdlmat

! exports desired sub file
*EXPORT, myse, sub, newse.sub, stiff, , done

!! To verify it works as expected
/clear ! start from scratch 

et, 1, 50 
se, newse 

eqslv, sparse
wrfull, 1

*DMAT, MatK_check, D, import, full, file.full, stiff
*EXPORT, MatK_check, apdl, apdlmat_check
shouldbe28 = apdlmat_check(2,2)
*stat, shouldbe28

Other Resources
Matrix Transfer between MATLAB and Ansys link
Export Stiffness Matrix from Ansys link
APDL Math Example link
Ansys's Website APDL Math Example link


Popular posts from this blog

ANSYS User Defined Results

Export Stiffness Matrix from Ansys

ANSYS APDL Syntax Highlighting editor